SOLIDWORKS – Bug Rover _ Part 3 – Carterpilar Design – Computer Aided Design & The 118 Elements

In this Part of Bug Rover design work, I’ll show you the 3 main components of the Carterpilar assembly. These are: The Star Gear, The Gear Cap, The Wheel and The Carterpillar. Let’s start:

THE STAR GEAR

STEP 1

Create a new part

STEP 2

On Front plane draw the following sketch and revolve it as complete cylinder.

STEP 3

On Front plane sketch another profile which is perpendicular on the cylindrical surface of the previous feature. And create another revolved feature as shown:

STEP 4

Add a new datum plane as an offset from Right plane through the top point of the sketch from the vertically revolved feature:

STEP 5

On plane 1 sketch a circle of Ø65 and extrude it by the mid-plane with 36mm at 10°

STEP 6

Add a fillet of 50mm on the mid-edge

STEP 7

Draw a sketch on Front plane and extrude it 2,5mm by mid-plane creating a sort of rib feature

STEP 8

On the frontal planar side sketch a circle of Ø40 and cut-extrude it through all

STEP 9

Create a cut-extrude feature on the base cylinder as shown:

STEP 10

Remove material from the front side of the base cylinder with a cut-extrude of 8mm deep.

STEP 11

Create a revolved feature as as midle shaft on the base cylinder as shown:

STEP 12

Create a construction sketch on the planar face of the base cylinder, then create a threader hole of M8 as follows:

STEP 13

Add chamfers as follows:

STEP 14

Add fillets as follows:

STEP 15

Circular pattern the threaded hole around the outer surface of the base cylinder for 8 instances egually spaced:

STEP 16

Circular pattern of the rib from side cylinder for 24 instances as shown:

STEP 17

Circular Pattern the vertical cylinder and every additional features attached to it around the central cylinder for 3 instances as shown:

STEP 18

Add appearace:

..with a better rendering in KeyShot the final part could look like this:

THE GEAR CAP

STEP 1

Create a new part

STEP 2

Create the following sketch on Right Plane and revolve it 360°

STEP 3

On the planar surface draw a circle as shown and extrude it through all:

STEP 4

Create the 2nd extrude cut as shown:

STEP 5

Add a small chamfer of 0,5mmx45° on the counterbore edge

STEP 6

Pattern the last 3 features around the outer surface as shown:

STEP 7

Add 2 fillets as shown.

STEP 8

Add appearance

…with a better rendering in KeyShot the final part could look like this:

THE WHEEL

STEP 1

Create a new part

STEP 2

On front plane draw the following sketch and revove it into a complete cylinder

STEP 3

Sketch a centerpoint arc slot on the inner planar surface and cut-extrude it through all

STEP 4

Add fillets and chamfer

STEP 5

Circular Pattern the slot cut-out and Fillet 2 around the outer cylindrical surface for 5 instances equally spaced:

STEP 6

Apply mirror feature for the entire body as shown:

STEP 7

Create a Ddatum plane placed in the middle of part as shown:

STEP 8

Add appearance

…with a better rendering in KeyShot the final part could look like this:

THE CARTERPILAR

STEP 1

Create a new part

STEP 2

Create the following sketch on the Front Plane and extrude it in 2 directions (60mm + 15mm)

STEP 3

Apply chamfers and fillets as follows:

STEP 4

Create a small groove on the top outer surface as an extruded-cut:

STEP 5

Add a fillet of 2 mm at the groove’s bottom

STEP 6

Convert the outer edges into a sketch on the front surface and use that curve to pattern the groove as Curve Driven of 100 instances egually spaced, as shown:

STEP 7

Similarly create another groove on the inner surface also an an Extruded-cut:

STEP 8

For the inner groove use the 1st Sketch created at STEP 2 as guide to create a Curve Driven Pattern of 100 instances on inner surface as shown:

STEP 9

Create a new datum plane as an 20mm offset from the frontal surface:

STEP 10

Use the Plane 1 to create a new feature as an Extruded Boss on the top area:

STEP 11

Add a fillet of 2mm on side edges:

STEP 12

Use the 1st Sketch created at STEP 2 as guide to create a Curve Driven Pattern of 40 instances with the previous extruded boss on inner surface as shown: